DIN/ISO Export

Contents:
DIN/ISO data export. DIN/ISO parameters. List of the DIN/ISO export filters. | Multiexp.Ser.No. (only for eSIGN2D, iSIGN+, HCAM).

DIN/ISO data export. The milling data are exported in the format for ISO, DIN66025 or a similar format. Depending on the export filter, milling data can be created for 3-axis- (X/Y/Z), for 4-axis (additional circular axis for surface processing) or for multiple-axis machines. You achieve the DIN/ISO data export via File . Export . DIN/ISO. DIN/ISO data can be saved in a file (standard export or autoexport) or also rendered via the aid direct mill auto directly in an output program (control program, e.g. WinPC-NC). The setting of the data export takes place in the window DIN/ISO export.
DIN/ISO FILTER | Selection of the export filter for a control system/machine. Standard export filters (X/Y/Z + rotational axis) are marked in black. Multi-axis export filters (4 and 5 axis) are marked in blue.
Start position X,Y | Position for the traversing of obstacles at the start of milling. For some newer export filters the starting position can be switched off using Startposn X =-9999.99 and Y=-9999.99. Then the first processing is approached in the NC data set.
Circular engraving diameter | Activation of the 4th axis for a cylindrical engraving. A circular engraving diameter = 0 (-0.001mm to +0.001mm) results in an output with the X,Y,Z axes. With negative values (<-0.001mm) the Y-axis (direction of rotation of the rotational axis) is mirrored. A rotational axis cannot be switched ON for multi-axis and turning machine export filters.
Cooling ON | With YES, with M8 in the data set, the cooling lubrication is switched ON.
Relieving position X,Y,Z | Movement following ending of the processing procedure. The input takes place for Z positive upwards. Depending on the export filter the relieving position Z can also be approached for tool exchange. W ith input of a negative relieving position in X and Y (e.g. X=-1 and Y=-1) no relieving position X/Y is approached. The relieving position Z, however, is always used.
Set number |
None | No set number issued.
1,2,3,.. | Set number (up to max.99999) with each set.
G0:1,2,. | Set number up to max.99999) with each contour (with G0).
10,20,.. | Set number with each set in steps of ten.
TOOL:1,2 | Set number only with tool exchange (Txx).
TStat-Add. Milling Path Monitoring | Additional tool exchange with exceeding of the tool life travel. The tool life travel (max. milling path) is given in the tool input. With the exceeding of the tool life travel a tool exchange is automatically induced. The current tool station number is the n incremented using the specified number (in the example = 10) (Example: specified TsT = 2 creates the series 2, 12, 22, 32 etc.). Data sets with autom. created tool station numbers may possibly have to be edited.
Parameter | Supplementary parameter input depending on export filter (see below: DIN/ISO Parameter).
OK | Input acknowledgement and, in addition, to input the file name for the milling data export.
Esc | Abort input and export.
Note: With the setting of the input parameter Arc tolerance > 0 (Aid in CAD), with export, as far as possible arcs are created within the set tolerance from frequency polygons. DIN/ISO Parameter. Parameter selection is dependent on the respective DIN/ISO export filter.
Tool exchange | M-Function (M6, M66, empty, M00) for a tool exchange (Txx). For Multicam (#25, #81) selection automat./manual.
Address rotational axis | Address of the rotational axis used (A, B, C) (dependent on the axis arrangement).
Rotational axis for... | Address of the linear axis (X, Y, none), which is to be replaced by the rotational axis.
For some export filters here, there are still some special settings possible (see below). List of the DIN/ISO export filters.
No. | Filter name | Suffix | Description
000 | Standard DIN / ISO | set. | General export with further settings under Parameter. Further DIN/ISO parameters:
With commentary [Y/N] | YES: show commentary text. N o: do not show commentary text.
Program heading | Text for program heading (Max. 16 symbols).
Arc [ABS/rel] | ABSOLUTE: arc G2/G3 I/J=absolute relative: arc G2/G3 I/J=relative
Program end | Text for program end (Max. 16 symbols).
Data expansion | Data expansion (e.g.. TXT).
001 | HEIDENHAIN DIN/ISO | DNC | Arcs G2/G3 I/J=absolute
002 | KÖRNER | PGM | Milling machines from the firm of CreativTec Gesellschaft f ür Präzisionssystem mbH, Barchfeld. Arcs G2/G3 I/J=relative
003 | EBERLE | NC | Milling machines from the firm of Werner Eberle GmbH, Pforzheim.
004 | BOSTOMATIC | TXT | Arcs G2/G3 I/J=absolute
005 | Kuhlmann FDIN | PRG | Milling machines from the firm of Kuhlmann Werkzeugmaschinen + Service GmbH, Bad Lauterberg. Arcs G2/G3 I/J=absolute Further DIN/ISO parameters:
Spindle run-up time [sec] | Delay 0..60 sec.
Z displacement [mm] | Surface relief offset in Z direction
Tool offset | None, G41, G42 for tool offset.
006 | DECKEL Dialog11 | NC | The tool exchange can alternative ly take place using 'T' (station number 1..999) and using 'TT' (station numbers 1001..1999). Example: Tool station number 7 results in 'T7', tool station number 1007 produces 'TT7'.
007 | ANDRONIC | ISO | Arcs G2/G3 I/J=absolute Further DIN/ISO parameters:
type of cooling [M8 / M7] | M8, M7 for cooling.
Measure feed (G188) [m/min] | Feed for tool measurement.
008 | HEIDENHAIN Cont12 | ISO |
009 | isel Intermediate format | NCP | Milling machines from the firm of isel Germany AG + imes-icore GmbH using Remote Program. Arcs G2/G3 I/J=absolute
010 | DIGMA-PC | ISO |
011 | MAHO-PHILIPS 432 | TXT | Arcs G2/G3 I/J=absolute
012 | ALLEN BRADLEY |  |
013 | MOVTEC | NC | A rcs G2/G3 I/J=absolute
014 | HECKERT | TXT |
015 | BENCHMAN 4000 | TXT |
016 | Mécanuméric | ISO |
017 | WABECO | ISO |
018 | Proteo FAGOR 8050M | TXT | Arcs G2/G3 I/J=relative
019 | DIGMA PC HSM4 | ISO |
020 | Eckelmann (ME) | DIN | Milling machines from the firm of Einzinger Maschinenbau, Gutenzell. Arcs G2/G3 I/J=relative
021 | VENTURE | CNC | Milling machines from the firm of VENTURE SRL. Arcs G2/G3 I/J=relative
022 | HEIDENHAIN Dialog | HNC |
023 | Walter-Seibu | TXT |
024 | FANUC O-MD | TXT | Arcs G2/G3 I/J=relative
025 | MultiCam | CNC | Milling machines from the firm of MultiCam LP, Dallas, Texas, USA. Arcs G2/G3 I/J=absolute Further DIN/ISO parameters:
With commentary [Y/N] | YES: show commentary text. No: do not show commentary text.
026 | MaxNC | T | Arcs G2/G3 I/J=relative
027 | ROTEX / Mitsubishi | TXT | Arcs G2/G3 I/J=relative
028 | Mazak Bearbeitungsz. | EIA | Milling machines from the firm of Yamazaki Mazak. Arcs G2/G3 I/J=relative
029 | KÖBLER CNC to 1990 | CNC | Arcs G2/G3 I/J=absolute
030 | FIDIA no TOOL | TXT | Arcs G2/G3 I/J=absolute
031 | Cobalm IDEA Plus | SBL |
032 | Mazak Drehm.Mark 1-3 | EIA | Turning machines from the firm of Firma Yamazaki Mazak. The circular engraving diameter creates the type of output: For engraving on flat surfaces: circular engraving diameter = 0 - created tool xx.0. For engraving on generated surface: circular engraving diameter <> 0 - creates tool xx.1. The prefix (+/-) of the circular engraving diameter controls the direction of rotation of the C axis. The file name may consist of 1..8 digits only. The tool No. to be presented is selected before export. Tool No. Form:
Integr.4 | 4-digit output for Integrex (e.g. T3100.0).
Integr.6 | 6-digit output for Integrex (e.g. T031000.0).
Revolver | 4-digit output for revolver machines (e.g. T3100).
W ith Tool correction No. [J/N]: With YES a >Tool Correction No.(=Tool No.) is created.
For 4-digit Tool No. | 00..99 (e.g. T3131.0 or T0707)
For 6-digit Tool No. | 000..255 (e.g. T031031.0 or T007007)
033 | FIDIA | TXT | Arcs G2/G3 I/J=absolute
034 | Siemens 8M | DID | Arcs G2/G3 I/J=relative
035 | Siemens 8M Sub-prog. | DID | Arcs G2/G3 I/J=relative
036 | Siemens 840D-LANG | MPF | Arcs G2/G3 I/J=relative
037 | BES-Grav | DIN | Milling machines from the firm of BES GmbH, Bad Zwischenahn. With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached. With 'Parameter . Variable Technology [Y/N] = YES' the technology data for feed XY, incised feed Z and Spindle rpm in variable is written in the program heading. With amendment of the variable the complete program can thus be adjusted. Arcs G2/G3 I/J=relative Further DIN/ISO parameters:
Variable technology [Y/N] | YES: employment of variables in the export.
038 | FANUC O-MA Drahterod. | TXT | Arcs G2/G3 I/J=relative
039 | Eckelmann MAchsen(ME) | DIN | Milling machines from the firm of Einzinger Maschinenbau, Gutenzell. 5-axis data export for Einzinger milling machines Arcs G2/G3 I/J=relative
040 | Röders RMS6 Gravur | ROD | Milling machines from the firm of Röders GmbH, Soltau. Traverse height between individual tasks: Withdrawn movement between the tool objects are fundamentally travelled at the height of the 'relieving position Z'. I.e. within a milling data set (for one tool) withdrawn movements are at the level of the safety height. Connections between individual milling objects are travelled at the height of the 'Relieving position Z'. Arcs G2/G3 I/J=absolute
041 | AutoGrav | NC | Milling machines from the firm of AutoGrav CNC-Systeme, Wesseling. You can set the arc output using 'Parameter .Arc [ABS/rel]'. Standard is 'relative'. In this case, with import in 'WinPC-NC', the parameter 'Data format . DIN/ISO G02/G03' must be set to 'relative'! Further DIN/ISO parameters:
Arc [ABS/rel] | ABSOLUTE: arcs G2/G3 I/J=absolute relative: arcs G2/G3 I/J=relative
042 | FANUC / HITACHI SEIKI | TXT | Arcs G2/G3 I/J=absolute
043 | FADAL VMC4020HT | NC | Arcs G2/G3 I/J=relative
044 | KUKA Roboter | TXT | Robots of the firm of KUKA SysTec GmbH.
045 | FlexiCAM | CNC | Milling machines from the firm of FlexiCAM GmbH, Eibelstadt. Arcs G2/G3 I/J=absolute
046 | MICROGRAV V4 | TXT | Milling machines from the firm of MicroGrav Rehmet & Voss GbR, Sendenhorst. Arcs G2/G3 I/J=absolute
047 | HEIDENH.DIALOG TNC407 | H |
048 | KOSY - MAX Computer | KNC | Milling machines from the firm of MAX Computer GmbH. Arcs G2/G3 I/J=relative
049 | BOSCH CC220 | TXT | Arcs G2/G3 I/J=relative
050 | CHARLYROBOT GPilote | ISO | Milling machines from the firm of Charlyrobot, CERNEX. Arcs G2/G3 I/J=absolute
051 | Siemens 810 | MPF | Arcs G2/G3 I/J=relative
052 | SELCA ISPER | DAT | Arcs G2/G3 I/J=relative
053 | MAHO MH600 | TXT | Arcs G2/G3 I/J=relative
054 | HEID.Dial. HermleC800 | H | For Hermle milling machines.
055 | Eckelmann-NCMind | DIN | Milling machines from the firm of NCmind OHG Pleikies & Fischer, Weilar. With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached. Arcs G2/G3 I/J=relative Further DIN/ISO parameters:
Program number | Program number in the heading of the ISO program.
Type of cooling [M8 / M7] | Selection of the cooling. Alternatively M7 or M8.
Contours with RotatA.switch | To switch the rotational axis (for special applications only).
All G0 to RelievPosnZ | With the setting 'YES' all G0 movements are carried out at the height of the relieving position Z. With 'No' the movements take place at safety height.
056 | isel-Knotenpkt.MM2000 | NC | Arcs G2/G3 I/J=relative
057 | MACH 2/3/4 Mitsubishi | PRG | Milling machines from the firm of Einzinger Maschinenbau, Gutenzell. Arcs G2/G3 I/J=relative Further DIN/ISO parameters:
Extract [Y/N] | YES: switch ON suction system.
Spray [J/N] | YES: switch ON spray cooling.
058 | WinPC-NC / PC-NC | NC | Milling output of the firm of Burkhard Lewetz, Meckenbeuren. Using 'Parameter .Arc [abs/rel]' you can set the arc output. Standard is 'relative'. In this case, with import in 'WinPC-NC', the parameter 'Data format . DIN/ISO G02/G03' must be set to 'relative'! Further DIN/ISO parameters:
Arc [ABS/rel] | ABSOLUTE: arcs G2/G3 I/J=absolute relative: arcs G2/G3 I/J=relative
059 | Eckelmann PASO | DIN | Milling machine of the firm of Paso Präzisionsmaschinenbau GmbH, Herzberg. Arcs G2/G3 I/J=relative
060 | Mazak M2 UP | EIA | Milling machine of the firm of Yamazaki Mazak. Arcs G2/G3 I/J=relative
061 | Kitamura Mycenter-5x | ISO | Arcs G2/G3 I/J=relative
062 | FAGOR LNC500 Ch.Liang |  | Arcs G2/G3 I/J=relative
063 | Andronic/8V Mikromat | HS1 | With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached.
064 | Siemens 840D-Unterpr. | SPF | This export creates sub-programs with tool exchange. Arcs G2/G3 I/J=relative
065 | MACH 8 - Mitsubishi | PRG | Milling machine of the firm of Einzinger Maschinenbau, Gutenzell. With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached. Arcs G2/G3 I/J=relative
066 | Eckelmann FLEXICAM C. | DIN | Milling machine of the firm of FlexiCAM GmbH, Eibelstadt. Arcs G2/G3 I/J=relative
067 | Philips 3000 | NC | Arcs G2/G3 I/J=absolute
068 | Heidenh.Dial. iTNC530 | H |
069 | Heidenh.Dial. TNC426 | H |
070 | Heidenh.Dial. TNC150 | NC | Without commentary without graphics, Set number from 0, no FMax; replaced by F5000, Suffix = .NC
071 | Heidenh.Dial. TNC155 | NC | Such as TNC150 (#70), however, with graphics (BLK FORM)
072 | Siemens 840D-Standard | MPF | Arcs G2/G3 I/J=relative
073 | Heid.Dia.T426 Auto.WW | H |
074 | Spinner PD Umfang840D | MPF | Export for Spinner turning machines for the engraving on generated surfaces. Control system: Siemens 840D. The changing positions are firmly set using X300 and Z150. For this task a rotational engraving diameter must be given. The Set Number is always given in steps of ten. With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached. Arcs G2/G3 I/J=absolute
075 | Spinner PD Stirn 840D | MPF | For Spinner turning machines, engraving on front face. Control system: Siemens 840D. Arcs G2/G3 I/J=absolute
076 | BEAMICON | TXT | Control systems from the firm of Benezan Electronics, Rottenburg. With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached. Arcs G2/G3 I/J=relative
077 | ANDRONIC KM2060 | ISO | Milling machines from the firm of Firma Kuhlmann Werkzeugmaschinen + Service GmbH, Bad Lauterberg. Milling data for Kuhlmann RUBIN with Andronic KM2060. With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached (not to the approach position X/Y). Further DIN/ISO parameter:
Tool adjustment | Adjustment of the tool gauging (laser, dynamometer, none).
Type of cooling [M8 / M7] | Selection of the cooling (M8, M7)
ZeroPtDispl G59 | YES: with zero point displacement G59.
Program end M30/M99 | Program end with M30 or M99.
078 | KÖRNER (Bohrzyklen) | PGM | Milling machine from the firm of CreativTec Gesellschaft für Präzisionssystem mbH, Barchfeld. Special milling data export for Körner control systems. With this export drillings (comp. draw . dot) are replaced by cycles (self- created DIN programs). All other movements remain unchanged. The cycle is saved in the file 'Cycle.PGM' and must be located in the program directory (comp. example file 'Cycle.PGM'). Before the implementation of the cycle, the Z axis travels to the start position on which the tool insertion depth is given. If the cycle is to start on the material surface, an insertion depth of 0mm is to be given. With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached. Arcs G2/G3 I/J=relative
079 | S&H CNC | GIO |
080 | XENETECH (INCH) | CNC | Arcs G2/G3 I/J=absolute
081 | Multicam G41/42 | CNC | Milling machines from the firm of MultiCam LP, Dallas, Texas USA. Alternative output to MultiCam Machines. For this export, in front of every contour, G41 or G42 can be set for an offset calculation using the control system under 'Parameter'. This special export is not suitable for the employment of a multihead cutter head. With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached. Arcs G2/G3 I/J=absolute Further DIN/ISO parameters:
With commentary [Y/N] | YES: show commentary text. No: do not show commentary text.
Tool offset | N one, G41, G42 for tool offset.
082 | Step Four | S4G | Milling machines from the firm of STEP-FOUR Vertriebs GmbH, Salzburg. Data export for Step Four control systems. This export supports no tool exchange. With approach posn X =-9999.99 + Y=-9999.99 the first processing position in the NC data set is always approached. Arcs G2/G3 I/J=relative
083 | Portatec-S840D | MPF | Milling machine from the firm of PORTATEC Maschinenbau GmbH, Schmorkau Arcs G2/G3 I/J=relative
084 | OKUMA OSP-U100M | MIN | Arcs G2/G3 I/J=relative
085 | ME HAAS | TXT | Arcs G2/G3 I/J=relative
086 | BZT Mach3 | TAP | Milling machines with Mach3 control systems. Arcs G2/G3 I/J=relative
087 | DECKEL FP3NC | TXT | Arcs G2/G3 I/J=relative
088 | Portatec Eckelmann EC | DIN | Milling machines from the firm of PORTATEC Maschinenbau GmbH, Schmorkau. Arcs G2/G3 I/J=relative Further DIN/ISO parameters:
Type of cooling [M8 / M7] | Selection of the cooling (M8, M7, M50)
089 | Mazak Mazatrol U-Prog | EIA | Milling machines from the firm of Yamazaki Mazak. Arcs G2/G3 I/J=relative
090 | FANUC Ser.31i Mod.A5 | TAP | Arcs G2/G3 I/J=relative
091 | Eckelm.PASO ECCPU 502 | DIN | Milling machines from the firm of Paso Präzisionsmaschinenbau Arcs G2/G3 I/J=relative
092 | PNC1 / Sicom 3000 | NC | Arcs G2/G3 I/J=absolute
093 | HEIDENHAIN TNC320 o.Z | H |
094 | PowerCut | CNC | Milling machines from the firm of Buth Graviersysteme, 27211 Bassum. Arcs G2/G3 I/J=relative
095 | VicCam | NC | Milling machines from the firm of Buth Graviersysteme, 27211 Bassum. Arcs G2/G3 I/J=relative
096 | AXYZ | TXT | Milling machines from the firm of Buth Graviersysteme, 27211 Bassum. Arcs G2/G3 I/J=relative
097 | Maho MH600-432 | TXT | Arcs G2/G3 I/J=relative Further DIN/ISO parameters:
Program number | Program number (1..999) in the heading of the ISO program.
098 | DECKEL Dialog4 (86) | TAP | Arcs G2/G3 I/J=relative
099 | Heidenh.iTNC530-DMU50 | H |
100 | WinPC-NC turning machines | NC | Milling machines from the firm of Hylewicz CNC Technik, Geldern. This export filter can be used only for turning using HEIZ milling machines. Milling axes are X and Z, Y only for positioning. The milling data are to be issued vectorised without arcs. The cutting line is given in AD in the quadrants +X, -Y and output with X and Z. Rotational engraving diameter and insertion feed are not used. Transformation: Mach. X = CAD X Mach. Z = CAD Y Mach. C = const. rpm.
101 | Eckelm.ExC66 Nutzentr | DIN | Special format (incomplete) without tool exchanger. Rotational axis is ignored.
102 | SpinnerPD UmfFanuc18i |  | For Spinner milling machines, engraving on generated surfaces (circumference) Rotational engraving diameter only positive values, Arcs are vectorised. Control system: Fanuc 18i Transformation: Mach. Z = CAD X Mach. C = CAD Y (conversion into deg.) Mach. X = CAD Z
103 | SpinnerPD StiFanuc18i |  | For Spinner turning machines, engraving on front face Control system: Fanuc 18i Arcs G2/G3 I/J=relative Transformation: Mach. X = CAD X * 2 Mach. C = CAD Y Mach. Z = CAD Z

Multiexp.Ser.No. (only for eSIGN2D, iSIGN+, HCAM). Some programs with CAD and text creation (eSIGN2D, iSIGN+, HCAM) use the special milling data export Multiexp.Ser.No. Using this milling data export several labels (2..9999 items) can be milled at the same output position. This export is suitable for several labels/engravings with ser. numbers, but can, however, also be used for other exports. Special commands can be introduced into the data set (see below) with DIN/ISO export, for interruption (separation) of the engraving after each label (stop, change of workpiece etc.). The complete milling process for all labels is saved in one file. The possibility of inserting special commands is possible for DIN/ISO export only. All other exports do not possess this supplementary function. Please check in your control system handbook whether and which control functions there are available in your control system. Preparatory activities. The commands that are to added be saved in ASCII Text files (SupplStart.txt = Commands before the label and SupplEnde.txt = Commands after the label) in the program directory of eSIGN2D/iSIGN+/HCAM before first usage (see example files in the program directory). The commands are saved as for normal DIN/ISO programs in the correct format for the export filter to be selected. This supplementary data may contain no set numbers!
;Example for isel ncp - supplementary command before the label FASTABS X0 Y5000 Z0 SETBIT A1.1 MOVEABS Z1000 FASTABS X1101 Y4322 Z0 RESBIT A1.1 MOVEABS Z-1000
Data creation (label creation).
1 | Input in 'Layout . Limits' the dimensions of an individual label.
2 | Input your text with Ser. No. and, as required, your graphic(s).
3 | Define the layer tool for the exporting layer.
Data export.
1 | For data export select Multexp.Ser.No.
2 | Select the layer to be exported.
3 | Input the desired Number of labels [2..9999]: . There must be at least 2 labels, max. 9999 labels selected. following confirmation the program creates a graphic with all labels. With Ser. No. several numbers are written one above the other.
4 | Select the desired DIN/ISO export filter.
If, following an export attempt, the same export is to be repeated, then the Ser. No. in the text must be set to the start value manually.